dome cut in surface???
Scott
I have a flat plane in my current model, I need to create a circular
depression in the center of this face. I'm not sure how to do it. I know
the 'dome' command with reverse direction will create a circular depression
but I need a face to pick to do that. I can cheat and extrude a post up
from the surface .001" at the right diameter, and then depress that face,
but this technique doesn't sit right with me.
Are there any better ways to do this?
Thanks
Scott
Malcolm B. Stephens
semi-circle to do a cut revolve?
Regards
Malcolm
"Scott" <bka...@hotmail.com> wrote in message
news:Xns90F66C905E...@63.209.170.208...
Kandor
<cCTb7.10779$Y6.55...@news3.rdc2.on.home.com>:
>Would it work to set a plane perpendicular to this surface, and use a
>semi-circle to do a cut revolve?
>
>Regards
>
>Malcolm
>
>
Yes it would! Thanks for that.
Hoel Per
You can model this, using just surfaces, by sketching a circle to use to
create a split line on your planar surface. Afterwards a sketch is required
for use as a "constraint curve" when a "surface-fill" feature is defined.
The filled surface uses the split line for the "patch boundary" and its dome
contour is controlled by the constraint curve. The endpoints of the
constraint curve should be made coincident with the patch boundary.
It's possible and quite easy, once you get the steps down...
I'll send you an elliptical example via separate e-mail.
Per O. Hoel
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Derek
You could do a surface revolve with your profile. The profile being
something like a quarter circle. After you revolve it 360deg use the
trim tools to cut out the inside area of the planar surface.
Derek
~~~~~~~~~~~~~~~~~~~~~~~~~~~~~
Todd
Revolved cut maybe.....
Todd
Radek
You shall simplify your flat face and create circular or elyptical one
by creating split line on you flat surface and then try to use dome,
Or try to use command shape with "constrain to" option used,
then you can use sketched lines to descripe your feature.
Radek
bka...@hotmail.com (Scott) wrote in message news:<Xns90F66C905E...@63.209.170.208>...
Jerry Steiger
Scott
It seems like the other approach of revolving a cut is a better approach,
but if you really want to use the dome command, you could put in a face to
dome with the split line command (Insert/Curve/Split Line).
Jerry Steiger
At Work Computers
Eric
radius set to half your dome, and doing a cut/revolve?
bka...@hotmail.com (Scott) wrote in message news:<Xns90F66C905E...@63.209.170.208>...
Mark Biasotti
zero offset surface. Use one or two constrait curve sketch to
determine the convex or concave.
Mark
Mr Atari
If you are the one...are you still in the business??? What program did you
use to make the design? Do You think that SolidWorks "has it" when using
surface modelling?
Regards
Mr Atari (Not worthy)
Mark Biasotti
> use to make the design? Do You think that SolidWorks "has it" when using
> surface modelling?
Who are you? Funny thing is that I use to work for Atari (1981 thru
1984) and was responsible for the 2nd generation 2400 gaming console.
Mr Atari
just wondering if You use SolidWorks today and if you're still in the
business of making home entertainment gear?
Regards
/ Mr Atari
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